Swaybar-Shaft Assembly Workshop 8 Bonded Contact.

Slides:

Advertisements

Similar presentations

ANSYS Model of a Cylindrical Fused Silica Fibre

Advertisements

Results Viewer Workshop 13D Postprocessing. Workshop Supplement November 1, 2002 Inventory # W D. Postprocessing Results Viewer Description.

Building Frame Workshop 4 Beam Modeling. Workshop Supplement October 30, 2001 Inventory # W Beam Modeling Building Frame Determine the deflections.

Module 9 Bonded Contact.

WS11-1 VND101, Workshop 11 MSC.visualNastran 4D Exercise Workbook Bracket.

3-D Bracket Workshop 10A Loading and Solution. Workshop Supplement February 7, 2006 Inventory # W A. Loading and Solution 3-D Bracket Description.

Module 5 Beam Modeling.

Workshop 4B Contact with Friction

Bolt Torque Workshop 3 Surface Effect Elements. Workshop Supplement October 30, 2001 Inventory # W Surface Effect Elements Bolt Torque Description.

Finite Element Method FEM Dr. Mohammed Al-Hazmi ANSYS Basics Lecture 4.

DesignXplorer Parameter Manager Workshop 9. DesignXplorer Parameter Manager Workshop Supplement August 26, 2005 Inventory # WS9-2 Workshop 9 – Goals.

Coupling and Constraint Equations Module 3. Training Manual October 30, 2001 Inventory # Coupling & Constraint Equations Just as DOF constraints.

Thermal Analysis Module 6. Training Manual January 30, 2001 Inventory # Thermal Analysis In this chapter, we will briefly describe the procedure.

Module 7 Modal Analysis.

Axisymmetric Analysis of a Pipe Assembly

Verifying Pressures Workshop 9 Macro Basics. Workshop Supplement October 30, 2001 Inventory # W Macro Basics Verifying Pressures Create a.

9.0 New Features Large Deformation Analysis of thin plate assembly spotwelded together Workshop 2 Spotwelds.

Advanced Results Processing Workshop 8. Training Manual Advanced Results Processing August 26, 2005 Inventory # WS8-2 Workshop 8 - Goals In this.

ANSYS Fundamentals This document contains no technical data subject to the EAR or the ITAR.

Large Deflection Arched Beam Workshop 7 Nonlinear Analysis.

University of Puerto Rico at Mayagüez Department of Mechanical Engineering Introduction to NX 6.0 Tutorial 1 Modified by (2011): Dr. Vijay K. Goyal and.

University of Puerto Rico at Mayagüez Department of Mechanical Engineering Introduction to NX 6.0 Tutorial 4 Modified by (2011): Dr. Vijay K. Goyal and.

Select Logic Module 11. Training Manual January 30, 2001 Inventory # Select Logic Overview Suppose you wanted to do the following: –Plot all.

Axisymmetric Wheel Workshop 1 Array Parameters. Workshop Supplement October 30, 2001 Inventory # W Array Parameters Axisymmetric Wheel Determine.

Problem 1: Structural Analysis of Signs Post University of Puerto Rico at Mayagüez Department of Mechanical Engineering Modified by (2008): Dr. Vijay K.

Workshop 6: Thermal Analysis of a Plate with a Hole University of Puerto Rico at Mayagüez Department of Mechanical Engineering Modified by (2008): Dr.

Static Structural Analysis Appendix Four. Training Manual Static Structural Analysis August 26, 2005 Inventory # A4-2 Basics of Linear Static Analysis.

9.0 New Features Metal Shaft with Rubber Boot Workshop 7 Load Steps in Workbench.

Thermal Analysis Appendix Six. Training Manual General Preprocessing Procedure March 29, 2005 Inventory # A6-2 Basics of Steady-State Heat Transfer.

Collapse of Frame Workshop Thirteen REFERENCE: Training Manual Geometric Instability (9-74)

Submodeling Module 6. Training Manual January 30, 2001 Inventory # Submodeling Submodeling is a finite element technique used to get more.

REFERENCE: Training Manual Obtaining the Solution (3-28) Fishing Rod (part 2) Workshop Three Results File Options.

Explicit-to-Implicit Sequential Solution

Investigation of the Thermal Stresses in a Steel Plate.

REFERENCE: Training Manual Node-to-Surface Elements (8-16) Beam Tip Contact Workshop 12 Node-to-Surface Elements.

Structural Analysis Chapter 10. Training Manual October 30, 2001 Inventory # In this chapter, we will describe the specifics of a structural.

Importing Geometry Workshop 5. Workshop Supplement October 30, 2001 Inventory # W Importing Geometry Description Import the following CAD.

Axisymmetric Rotating Disk Workshop 3A Optimizing the Design.

Batch Mode: Plate with Hole at Center Workshop 13A Short Topics.

Surface-to-Surface Simulation

Input Files for Workshop Exercises Workshop Supplement Appendix A.

Workshop 13 Bolt Pretension

Workshop 1 Contact Stiffness

Springback Analysis Workshop 10. Workshop Supplement March 15, 2001 Inventory # WS10-2 Utility Menu > File > Read Input from … > stamp.inp > OK.

Rib Forging Workshop Nine REFERENCE: Training Manual Viscoplasticity (5-35)

Volumetric Locking Workshop Two REFERENCE: Training Manual Element Technology (2-64)

Lathe Cutter Workshop 2A Stress Analysis. Workshop Supplement January 20, 2001 Inventory # W2-2 2A. Stress Analysis Lathe Cutter Description Solve.

Buckling of Arch Workshop Twelve REFERENCE: Training Manual Geometric Instability (9-56)

Pillow Block Workshop 6 Solid Modeling: Top-Down.

Modal Analysis Advanced Topics Module 8. Training Manual January 30, 2001 Inventory # Module 8 Modal Analysis - Advanced Topics A. Learn how.

Snap Fit Workshop Seventeen Introduction to Contact REFERENCE: Training Manual Introduction to Contact (7-69)

Bending of a Pipe by a Punch Workshop 8. Workshop Supplement March 15, 2001 Inventory # WS8-2 Utility Menu > File > Read Input from … > pipe.inp.

General Troubleshooting Nonlinear Diagnostics. Goal – In this workshop, our goal is to use the nonlinear diagnostics tools available in Solution Information.

NLISO Material Model Workshop Four REFERENCE: Training Manual Rate-Independent Plasticity (3-65)

Simulating a Deep Drawing Process Workshop 2. Workshop Supplement March 15, 2001 Inventory # WS2-2 Utility Menu > File > Read input from …> deep.inp.

Element Birth & Death Chapter Ten

Truss Structure Workshop Five Convergence Criteria REFERENCE: Training Manual Obtaining the Solution (3-51)

Crank Shaft Workshop 5 Submodeling. Workshop Supplement October 30, 2001 Inventory # W Submodeling Crank Shaft Description Perform a submodeling.

Copyright © 2007 by Pearson Education 1 UNIT 6A COMBINATIONAL CIRCUIT DESIGN WITH VHDL by Gregory L. Moss Click hyperlink below to select: Tutorial for.

REFERENCE: Training Manual Friction (4-18) Planar Seal (part 2) Workshop 2 Contact with Friction Constant Friction Coefficient.

Stress Relaxation Workshop Six REFERENCE: Training Manual Implicit Creep (4-32)

ANSYS Basics Workshop 3A Introductory Workshop. Workshop Supplement October 30, 2001 Inventory # W3-2 3A. Introductory Workshop ANSYS Basics In.

ANSYS Basics Workshop 1 Introductory Workshop. Workshop Supplement January 30, 2001 Inventory # W1-2 Introductory Workshop ANSYS Basics In this.

Connecting Rod Workshop 7A Solid Modeling: Bottom-Up.

Chapter Overview In this exercise, a model of a cylindrical pipe is modeled as being crushed between rigid bodies. This model is created using 2D shell.

WORKSHOP 7 LINEAR CONTACT

WORKSHOP 14 KNOWLEDGEWARE

NECKING OF A TEST SPECIMEN

Module 6 Submodeling.

Presentation transcript:

Swaybar-Shaft Assembly Workshop 8 Bonded Contact

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly Description A swaybar-shaft assembly is subjected to a vertical force of 500 kgf at the right end of the swaybar. The objective is to determine the overall stresses in the assembly. Use bonded contact to simulate the assembly, and replace the right two- thirds of the swaybar with a "rigid region" (constraint equations). As a follow-up, join the two parts using a Boolean glue operation and redo the analysis.

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly Loads and Material Properties

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 1.Enter ANSYS in the working directory specified by your instructor using “bonded- contact” as the jobname. 2.Read input from the file “bonded-contact.inp” to 1) mesh the model, 2) create rigid links, and 3) apply constraints and loads: –Utility Menu > File > Read Input from … –Or issue: /INP,bonded-contact,inp 3.Create the bonded contact elements between the shaft and the swaybar: Procedure shown on following pages

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 3.(cont’d) a) Create the contact elements: –Main Menu > Preprocessor > -Modeling- Create > Contact Pair > Contact Wizard … Select “Flexible” and “Areas”, then [Pick Target …] Pick area 48, then [OK] HINT: drag mouse until Area 48 is selected or type 48 into the input window, then Enter For ambiguous pick, hit NEXT until “48” is selected Pick [Next >] Select “Areas”, then [Pick Contact …] Pick area 22, then [OK] Pick [Next >] Pick [Optional settings …] Set the “Normal Penalty Stiffness” to 100 Select “Bonded (always)” for Behavior of contact surface Select the “Initial Adjustment” tab Select “Exclude everything” for Initial penetration [OK] [Create >] [Finish]

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 3.(cont’d) b) select type 5 elements and their nodes and then plot the target surface contact elements: –Utility Menu > Select > Entities... –Main Menu > Preprocessor > -Modeling- Create > Contact Pair > View Pair … Select “Target Surface” and check “normals shown” under Options [Display] –Utility Menu > Plot > Elements –Or issue: ESEL,S,TYPE,,5 NSLE /PSYMB,ESYS,1 /PNUM,TYPE,1 EPLOT

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 3.(cont’d) c) Select type 6 elements and their nodes and then plot the contact surface contact elements: –Utility Menu > Select > Entities... –Main Menu > Preprocessor > -Modeling- Create > Contact Pair > View Pair … Select “Contact Surface” and check “normals shown” under Options [Display] –Utility Menu > Plot > Elements –Or issue: ESEL,S,TYPE,,6 NSLE /PSYMB,ESYS,1 /PNUM,TYPE,1 EPLOT d) Close the “View Contact Pair…” window [Close]

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 4.Select everything, turn off all symbols except constraint equations, then plot elements: –Utility Menu > Select > Everything –Utility Menu > PlotCtrls >Symbols > For Individual : Miscellaneous > Constraint Equations –Utility Menu > Plot > Elements –Or issue: ALLSEL /PBC,CE,,1 /AUTO,1 EPLOT

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 5.Enter the solution processor and turn off solution controls. Then choose the PCG solver, set the number of equilibrium iterations to one, and solve: –Main Menu > Solution > Unabridged Menu –Main Menu > Solution > -Load Step Opts- Solution Ctrl.. Set to “Off”, then [OK] –Main Menu > Solution > -Analysis Type- Sol’n Control... Pick the “Sol’n Options” tab Select “Pre-Condition CG” Pick the “Nonlinear” tab Enter “1” for the number of Equilibrium Iterations [OK] Read and then close yellow warning message window –Pick the “SAVE_DB” button in the Toolbar (or select: Utility Menu > File > Save as Jobname.db) –Main Menu > Solution > -Solve- Current LS –Or issue: /SOLU SOLCONTROL,OFF EQSLV,PCG NEQIT,1 SAVE SOLVE

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 6.Unselect element 8000 (MASS21 element), then enter POST1 and plot the nodal von Mises stresses: –Utility Menu > Select > Entities... –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... –Or issue: ESEL,U,,,8000 /POST1 /AUTO,1 PLNSOL,S,EQV

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 7.Plot von Mises stresses for elements associated with volume component “v_bar”: –Utility Menu > Select > Comp/Assembly > Select Comp/Assembly … –Utility Menu > Select > Everything Below > Selected Volumes –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... –Or issue: CMSEL,S,v_bar ALLSEL,BELOW,VOLU PLNSOL,S,EQV

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 8.Plot von Mises stresses for elements associated with volume component “v_shaft”: –Utility Menu > Select > Comp/Assembly > Select Comp/Assembly … –Utility Menu > Select > Everything Below > Selected Volumes –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... –Or issue: CMSEL,S,v_shaft ALLSEL,BELOW,VOLU PLNSOL,S,EQV

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 9.Now rerun the stress analysis, with the swaybar and shaft volumes glued together, by reading input from the file “swaybar-shaft-glued.inp”: –Utility Menu > File > Read Input from … –Or issue: /INP,swaybar-shaft-glued,inp 10.After the solution completes, the nodal solution for SEQV is displayed for the swaybar (i.e. v_bar volume component):

Workshop Supplement October 30, 2001 Inventory # W Bonded Contact Swaybar-Shaft Assembly 11.Plot von Mises stresses for elements associated with volume component “v_shaft”: –Utility Menu > Select > Comp/Assembly > Select Comp/Assembly … –Utility Menu > Select > Everything Below > Selected Volumes –Main Menu > General Postproc > Plot Results > -Contour Plot- Nodal Solu... –Or issue: CMSEL,S,v_shaft ALLSEL,BELOW,VOLU PLNSOL,S,EQV 12.Exit ANSYS.