1. 7-1 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Chapter 7 Introduction to MultiZone Meshing ANSYS Meshing Application Introduction

2. Introduction to MultiZone Meshing 7-2 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Overview Comparing Sweep and MultiZone Comparing Thin Sweep and MultiZone Example for Sweep, Thin Sweep, and Multizone Methods Approach for the MultiZone Method MultiZone Method Settings – Mapped Mesh Type – Free Mesh Type – Source Selection – Defeaturing Inflation and MultiZone Workshop 7.1 MultiZone Meshing for a Block Geometry with Pipes Workshop 7.2 MultiZone Meshing for a Tank Geometry with Piping

3. Introduction to MultiZone Meshing 7-3 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Comparing the Sweep and MultiZone Methods Sweep Method: Sweeps a single source/face to a single target/face. Does a good job of handling multiple side faces along sweep Geometry needs to be decomposed so that each sweep path is represented by 1 body. Some models can be meshed with either approach MultiZone Method: Free decomposition approach Multiple sources to multiple targets

4. Introduction to MultiZone Meshing 7-4 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Sweep or MultiZone? Use Sweep Method when: You have a multibody part where some bodies should be meshed with Sweep, and some with Patch Conforming Tet – If you want to use advanced size function Preview Sweepable bodies shows that all bodies are sweepable Use MultiZone when: You are meshing single body parts that are too complicated for traditional sweep approach. You have multiple sources and targets you need to respect (can’t use VTs to group into a single source/target) You need to inflate off source and side faces

5. Introduction to MultiZone Meshing 7-5 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Comparing Thin Sweep and MultiZone Some models can be meshed with either approach MultiZone Method: Free decomposition approach Multiple sources to multiple targets Thin Sweep Method: Sweeps multiple sources to paired multiple targets Good substitute for midsurfacing shell models to get a pure hex mesh

6. Introduction to MultiZone Meshing 7-6 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Thin Sweep or MultiZone? Use Thin Sweep Method when: You have a “thin” solid part where the source and target faces don’t exactly match, and you don’t care about the features on the target side. Use MultiZone When: You have a “thin” solid part where the source and target faces don’t exactly match, and you care about the features on both sides.

7. Introduction to MultiZone Meshing 7-7 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Different Sweep Methods Example Sweep Method: Thin Sweep Method: MultiZone Method: For Example

8. Introduction to MultiZone Meshing 7-8 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Sweep Method Treatment Use VTs to merge multiple sources into 1 source Multiple sources ignored Multiple targets ignored Use VTs to merge multiple targets into 1 target

9. Introduction to MultiZone Meshing 7-9 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Thin Solid Sweep Treatment Multiple source Multiple target Multiple sources captured Multiple targets ignored

10. Introduction to MultiZone Meshing 7-10 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual MultiZone Method Sweep treatment Multiple source Multiple target Multiple sources captured Multiple targets captured Note, MultiZone will ignore the internal cutouts unless they are in a Named Selection

11. Introduction to MultiZone Meshing 7-11 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Multizone Method Approach Multizone features automatic geometry decomposition which avoids the need to slice a body up into sweepable bodies to get a hex mesh with the sweep method For example, the geometry shown at right would need to be sliced into three bodies to get a hex mesh with sweep. With the Multizone method, a hex mesh could be generated directly – Based on ICEM CFD Hexa blocking – O-grids can be extruded to create inflation – Unstructured regions can be filled with hex- dominant, hex-core, or tetrahedral mesh

12. Introduction to MultiZone Meshing 7-12 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Multizone Method Settings Multizone will not utilize the Advanced Size Function (Patch Conforming Tet and Sweep Methods only) Source selection is not mandatory, but may be helpful Can exclude or allow free mesh blocks

13. Introduction to MultiZone Meshing 7-13 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Multizone Method Settings Mapped Mesh Type – Hexa – Hexa/Prism Free Mesh Type – Not Allowed – Tetra – Hexa Dominant – Hexa Core Source/Target Selection – Automatic – Manual Source Advanced – Defeaturing Tolerance – Minimum Edge length

14. Introduction to MultiZone Meshing 7-14 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Multizone Method and Inflation Algorithm different from other inflation methods (extruded o- grid) Scoped to bodies, defined for faces Only First Layer or Total Thickness options

15. 7-15 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Multizone Meshing for a Block Geometry with Pipes Workshop 7.1

16. Introduction to MultiZone Meshing 7-16 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Goals This tutorial will illustrate basic use of the Multizone method to create a Hex mesh for a simple geometry with the addition of an inflation layer. Source selection for the multizone sweep will be done automatically by the mesher when the mesh is generated.

17. Introduction to MultiZone Meshing 7-17 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Importing Geometry 1.Copy the blockandpipes.agdb file from the Tutorial Files folder to your working directory 2.Start Workbench and double- click the Mesh entry in the Component Systems panel 3.Right-click on Geometry in the Mesh entry in the Project Schematic and select Import Geometry/Browse 4.Browse to the block and pipes.agdb file you copied and click Open. Note that the Geometry entry in the Project Schematic now has a green check mark.

18. Introduction to MultiZone Meshing 7-18 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual 5.Double click the Mesh entry in the Mesh object on the Project Schematic to open ANSYS Meshing 6.Close the Meshing Options Panel at the right without setting anything. 7.Right-click on Mesh and insert a Method. Select the body and set the method to Multizone. Leave the settings as the defaults as shown Insert Multizone Method

19. Introduction to MultiZone Meshing 7-19 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Mesh Sizing and Metric 8.Click on Mesh in the Outline 9.Change the Physics Preference to CFD and the Solver Preference to Fluent 10.Expand the Sizing Entry and turn off the Advanced Size Function (it will not be used for Multizone anyway) 11.Set the Element Size to 0.20 [in]. (Note: if the units are set to some other system, click on Units in the Menu Bar and change to U.S. Customary (in, lbm, …) 12.Expand the Statistics entry and set the Mesh Metric to Skewness

20. Introduction to MultiZone Meshing 7-20 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Mesh and Mesh Quality 13.Generate the Mesh. Note the Mesh count and Skewness metric

21. Introduction to MultiZone Meshing 7-21 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Inflating the Multizone Method 14.Insert Inflation for the Multizone Method. Pick the outer cylindrical faces of the pipes and the 4 side faces of the block as the Boundary. Set the Inflation Option to Total Thickness with a value of 0.20 [in]. 15.Generate the mesh.

22. 7-22 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Multizone Meshing for a Tank Geometry with Piping Workshop 7.2

23. Introduction to MultiZone Meshing 7-23 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Goals This tutorial will show how to use the Meshing Application in ANSYS 12 to generate a mesh suitable for a CFD simulation of a chemical process flow. The geometry, consists of three bodies representing a tank together with a single inlet and outlet pipe. The goal is to produce an Hex mesh throughout the domain without any further decomposition of the geometry using the Multizone Method.

24. Introduction to MultiZone Meshing 7-24 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Creating a Standalone Meshing System 1.Launch ANSYS 12.0 Workbench from the START menu 2.Open the Component Systems section of the Toolbox on the LHS of the WB GUI. 3.Double click the Mesh option

25. Introduction to MultiZone Meshing 7-25 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Importing the Geometry 4.Right click on the Geometry button in the RHS of the WB panel and select Import geometry (the question mark on the button turns to a tick once a geometry file is imported) 5.Import the 2-pipe-tank.agdb file 6.Double click on the Mesh button to launch the Meshing Application

26. Introduction to MultiZone Meshing 7-26 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Geomety 7.The original geometry was modified in DesignModeler The tank was split into three bodies and some simplification was made to remove small faces that are not important to the analysis One multi-body “Part” was created and a given the name “Fluid” and the material type “Fluid” Individual bodies were re-named

27. Introduction to MultiZone Meshing 7-27 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual 8.In the Meshing Options panel to the RHS of the main window select the following meshing options: – Physics Preference CFD – Mesh Method Automatic – Click OK after you made the selections – In Units, make sure it is set to Metric, mm Meshing Options

28. Introduction to MultiZone Meshing 7-28 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Named Selections 9.Named Selections are used to assign Fluent name and zone types Set the Cursor Mode to Face selection Select the inlet face RMB select Create Named Selection Assign the name Inlet Repeat for Outlet A naming convention has been established to automatically assign zone types in Fluent For example - – “Inlet” Velocity-inlet zone –“Outlet” Pressure-outlet zone See Fluent Mesh export section of the manual for all options.

29. Introduction to MultiZone Meshing 7-29 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Global Mesh Settings 10.Set Global Size and Quality control Click on Mesh in the Model Tree to open up the Details of “Mesh” panel Sizing –Turn Off Use Advanced Size Function Multizone does not use this option –Change the Relevance Center Fine Recommended for most CFD applications that apply the Multizone Method Statistics –Assign Mesh Metric Option Skewness Maintain all other defaults

30. Introduction to MultiZone Meshing 7-30 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Inserting a Multizone Method 11.Insert Mutizone Meshing control Set the Cursor Mode to Body selection RMB (in Window) – Select All the bodies RMB (in Tree) – Insert – Method Select Multizone

31. Introduction to MultiZone Meshing 7-31 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Setting Multizone Sources 12. Select Mutizone Source faces Change Src/Trg Selection – Manual Source –To ensure the middle section can be swept Set the Cursor Mode to Face Pick the five green source faces (see top image) Rotate the model to look at the rear of the tank Pick the additional five red source faces (see bottom image) Apply

32. Introduction to MultiZone Meshing 7-32 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Generating the Initial Mesh 13. Create an initial Mesh of the model RMB (in Tree) – Generate Mesh The mesh is successfully created – but refinement is clearly needed – The mesh at the inlet and outlet pipes and close to the pipe/tank intersection is insufficient to capture the physics correctly – This can be achieved by inserting some additional meshing instructions such as Inflation, Sizing and Biased Sizing to improve the pipe/tank meshing

33. Introduction to MultiZone Meshing 7-33 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Face Sizing 14. Add Face Sizing for the pipes to control the size of elements Start by removing the mesh –RMB (in Tree) – Clean and confirm Make sure you’re using Face Selection and pick the four faces shown in Green RMB (in Tree) – Insert – Sizing Set Sizing Details : Set Element Size –1 mm

34. Introduction to MultiZone Meshing 7-34 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Adding Inflation 15. Add Inflation (boundary layers) Set the Cursor Mode to Body Selection Select the central green body RMB (in Tree) – Insert – Inflation 16. Set Inflation Details Switch to Face selection Select the four green cylindrical faces and Apply Set Inflation Control –Number of Layers 2 –Maximum thickness 1 mm

35. Introduction to MultiZone Meshing 7-35 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Edge Sizing 17.Add Edge Sizing Change Cursor Mode to Edge Selection Select two green edges on one side Rotate the model Repeat the selection RMB (in Tree) – Insert – Sizing 18.Set Sizing Details Element Size –1mm Behaviour –Hard Bias type –_ __ ___ __ _ Bias Factor –6

36. Introduction to MultiZone Meshing 7-36 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Generating the Final Mesh 19.Generate the mesh RMB (in Tree) – Generate Mesh Statistics –Elements ~45,000 –Max Skewness Below 0.8 Overall a good Quality mesh

37. Introduction to MultiZone Meshing 7-37 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Examining the Mesh 20.Examine the Mesh Inflation – on the pipe walls Sizing – 4 elements on face Sizing – element size 1mm across pipe and biasing to increase density at transition

38. Introduction to MultiZone Meshing 7-38 ANSYS, Inc. Proprietary © 2009 ANSYS, Inc. All rights reserved. April 28, 2009 Inventory #002645 Training Manual Saving the Project 21.The mesh is now complete RMB (Tree) select Update Select File > Close Mesh to close the Mesh application In the WB panel select File > Save Project As… and give the project a name Exit from ANSYS Workbench by selecting File > Exit 22.Further Work Change the mesh settings for each of the additional parameters –How do each of these parameters influence the mesh?